Whether you do wood carving or print with a 3D Printer like me. There is a maker spirit inside every person.

You’re in the perfect place if you enjoy figuring out solutions to issues you run into at home. In this blog post, we will create a simple but functional Hair Dryer Holder step by step. If you’re new to the maker business, don’t shy! I detailed the entire process, from measuring with a caliper to printing on a 3D printer, using animations, visuals, and, finally, video.

We will use xDesign application while designing.

Design Preparation

I believe it is necessary to determine our needs before beginning the design.

I wanted the Hair Dryer Holder to have the following features.

• Ability to hold the hair dryer
• Ability to hold the socket of the hair dryer
• Ability to hold a brush comb

We require some parameters based on these features.

Hair Dryer Body

Dimensioning Time!

The bodies of hair dryers are generally in a conical structure. The place where the body will sit should be designed accordingly. With a simple animation, I demonstrated the measurements that must be taken on the body.

We need to add a sitting/working gap to the values we measured with the caliper. In 3D printers, this value is in the 0.25-0.30 mm range from edge to edge. For example, if the measured value is 12 mm and the sitting gap is 0.25 mm, the resulting value is 12+0.25+0.25 = 12.50 mm.

Step 1: Using a caliper, measure the diameter of the base cone. The diameter value is measured as 65 mm, as shown in the animation. When we add the sitting gap, we get 65+0.5 = 65.5 mm.

Step 2: Determine the Holder body height that will surround the Hair Dryer Body before measuring the Second conical diameter. The measure here is entirely up to you. If the hair dryer is large, I recommend increasing the length here.

Step 3: Using a caliper, measure the diameter of the ceiling cone. The diameter value is measured as 70 mm, as shown in the animation. When we add the sitting gap, we get 70+0.5 = 70.5 mm.

Design Time!

Open the xDesign application in the 3D Creator Role if you are using the Maker License or Commercial License. The xDesign application must be launched from the 3D Designer Role in the academic license. A Dashboard can be used directly from there if you already use one.

We create a new component called Hair Dryer Holder by selecting New Component from the xDesign welcome screen.

We draw the shape in the gif by opening a sketching on the YZ plane and entering the values we measured with a caliper. As the wall thickness, we enter 3 mm. We enter half of the Diameter values because we will create a solid by revolving. In the Features menu, we select the Revolve command and create a solid body by selecting the axis line.

In this step, we will create the surface that will come into contact with the bathroom wall. This surface must be flat because we will use double-sided tape to attach the holder to the wall. To accomplish this, we select the YZ plane and use the Plane command from the shortcut menu to create a plane at a distance of 42 mm in the opposite direction.

By selecting this plane, we can open a new sketching and draw the rectangle and square shown in the image.

In the Features menu, we select the Extrude command. First, we will extrude the rectangle. To accomplish this, we delete the selected sketching in Profiles and select the rectangle’s sketch area. We select and confirm the conical body we created earlier by selecting Up To Geometry as the direction.

We make Sketch 2 visible from the feature tree.

After the Extrude command, we select the square sketch area. Here we set the thickness as 3 mm.

Using Design Assistance for Selection, we apply 2.5 mm Fillet and Champer to the edges.

Hair Dryer Socket

Dimensioning Time!

Step 1: Use a caliper to measure the protrusion on the back of the socket. Here we measured the long side. The length value is measured as 12 mm, as shown in the animation. When we add the sitting gap, we get 12+0.5 = 12.5 mm.

Step 2: Use a caliper to measure the protrusion on the back of the socket. Here we measured the short side. The length value is measured as 10 mm, as shown in the animation. When we add the sitting gap, we get 10+0.5 = 10.5 mm.

Design Time!

The body design of our holder is finished. Now it’s time to design the ears that will carry the socket and comb. We open a new sketching by selecting the base of the conical body and draw the ear on which the socket will sit. We use the Slot option in the Sketch menu to make this. To intersect the base’s circular edge and the slot drawing, select the circular edge and then select the Convert Entities command from the shortcut window that appears. After pruning and lengthening, our drawing will look like this.

With the Extrude command, we create a solid geometry with a thickness of 6 mm. We apply 5 mm champer to the edge that intersects with the conical body. The goal is to increase the strength here.

We mirror our solid part on the ZX plane using the mirror command. Our mirrored part will include a slot for the brush comb.

With the help of a caliper, we draw a rectangle measuring 12.50 x 10.50 mm on the solid surface (Right ear) that we have created according to the measurements we have measured. We create another rectangle that passes through the midpoint of the bottom edge of this rectangle. The gap to be created here will form the area where the cable will enter. We empty the space here with the Extrude Cut command.

Brush Comb

Dimensioning Time!

Step 1: Measure the largest diameter of the brush comb’s handle. The diameter value is measured as 14 mm, as shown in the animation. When we add the sitting gap, we get 14+0.6 = 14.6 mm.

Design Time!

With the help of a caliper, we draw a circle measuring 14.6 mm on the solid surface (Left ear) that we have created according to the measurements we have measured. Here, we add a larger sitting gap because of the friction. We empty this area with the Extrude Cut command.

Finally, we apply 1.25 mm Champer to the sharp edges of the ears that will carry the Socket and Comb.

Print Time!

We export our design in STL format. You can set the resolution of the STL format when exporting. Here we exported to be of maximum quality. After exporting, we slice it with a slice software in the settings specified in the video and transfer it to our 3D printer.

 

⬇️Click on the link to download the model⬇️

Our model is now ready for printing.